NX How to Add a Materials Column to a Parts List and Set It as a Default Parts List

How to Add a Materials Column to a Parts List and Set It as a Default Parts List.

Creating the Materials Column: Method 1

1.       Choose the Home tab -> Table group -> Parts List.

2.       In the Parts List dialog, under the Settings group select Settings.

3.       In the Parts List Settings dialog, expand the Parts List group and choose Column.

4.       Under the Behavior group, select Add New Column.

-          Note: To change the column order, use the Move Up and Move Down buttons.

5.       Under the Content group, click Attribute Name.

6.       In the Attribute Name, dialog, select the desired attribute – in this case, the Material attribute.

7.       Click OK.

8.       Click Close.

9.       Click on the drawing to place the Parts List.

Creating the Materials Column: Method 2

1.       Choose the Home tab -> Table group -> Parts List.

2.       Click on the drawing to place the Parts List.

3.       Select the column on the parts list that the materials column will be placed beside.

4.       Right click and select either Columns to the Left or Columns to the Right.

5.       Select the newly created column.

6.       Right click and choose Settings.

10.   In the Parts List Settings dialog, expand the Parts List group and choose Column.

11.   Under the Behavior group, select Add New Column.

-          Note: To change the column order, use the Move Up and Move Down buttons.

12.   Under the Content group, click Attribute Name.

13.   In the Attribute Name, dialog, select the desired attribute – in this case, the Material attribute.

14.   Click OK.

15.   Click Close.

Creating a Default Parts List

1.       In the top left corner of the parts list, hover over the square and right click.

2.       Choose Save As Template.

3.       In the File Explorer window, navigate to the desired location to save the template to.

4.       Enter the file name.

5.       Click OK.

6.       Choose File -> Utilities -> Customer Defaults.

7.       In the Customer Defaults dialog, select Drafting, then General/Setup.

8.       Select the Standard tab.

9.       Change the Drafting Standard to the desired standard to edit and click Customize Standard.

10.   Expand the Table group and choose Parts List.

11.   Under the Format group, click the Default Parts List: Native Mode text box.

12.   Enter the path to the template file and the exact file name preceded by a backslash.

-          Note: I.e. D:\FolderContainingTemplates\TemplateFile.prt

-          Note: Other options are as follows:

13.   Click Save As.

14.   In the Save As Drafting Standard dialog, enter the desired name for the custom drafting standard.

15.   Click OK.

16.   In the Customer Defaults dialog, click OK.

-          Note: The newly created drafting standard will be set as the current drafting standard.

Setting the Environment Variable

Note: Restarting the NX session is necessary to apply all settings in the newly created drafting standard. Before reopening NX, set the environment variable UGII_IGNORE_INTERNAL_PLIST = 1

1.       Before restarting NX, open System Properties.

2.       In the System Properties window, click Environment Variables.

3.       In the Environment Variables window, under the System Variables, click New and enter the information as follows:

-          Variable name: UGII_IGNORE_INTERNAL_PLIST

-          Variable value: 1

4.       Exit all windows by clicking OK.

-          Note: Upon restarting, NX will now apply customized drafting standard settings.