NX Customized parts list template in NX Manager mode

How to configure customized parts list template in NX managed mode?

Follow below steps to create custom parts list.

1. In the Drafting application, choose Menu → Insert → Table → Parts List.

The default parts list is added to the drawing. The default columns provided are:

PC No.

Part Name

Qty

2. Add additional columns as necessary. The PC No. column is the CALLOUT column by default.

3. To make another column the CALLOUT column:

Add the new column.

Right-click on the column and choose Select → Columns to select the column.

Right-click the column and choose Style.

The Annotation Style dialog box is displayed.

Click the Columns tab.

Enter the following:

CALLOUT in the Attribute Name box

<W$=@CALLOUT> in the Default Text box.

Click OK.

4. Right-click the parts list and choose Save As Template to save the parts list as a new template. Enter values for Number, Revision, and Item Name.

5. Choose File tab → Utilities → Customer Defaults.

6. Choose Drafting → General/Setup → Standard tab.

7. Select the drafting standard and click Customize Standard.

8. In the Customize Drafting Standard dialog box, choose Table → Parts List.

9. In the Format group, Default Parts List: TCIN mode box, type @DB/ then the file name and revision of your custom parts list template. For example:

@DB/my_template/A

10. Click Save to save the changes to the current drafting standard or click Save As and in the Save As Drafting Standard dialog box, enter the name for the new standard.

11. Click Cancel to exit the dialog box.

12. You must exit and restart NX to set the default for all NX sessions. Use this new template to provide proper synchronization between NX and Teamcenter.

Before launching NX, set UGII_IGNORE_INTERNAL_PLIST=1

Note: 

The UGII_IGNORE_INTERNAL_PLIST environment variable must be set if you want the default parts list to be the one you specified in the Customer Defaults dialog box.