NX How to displace Rotation symbol for the Section View Label: changing Text formatting

Sometimes customers Standards require to place Rotation symbol in the end of the Section View Label.
e.g.
1) Letter, 2) Scale label, 3) Rotation symbol and Angle.

But NX Drafting View Settings have no options to place Rotation symbol at this location.

Solution

Changing Section View Label by Formatting Text:

- open "Section View Settings \ Section Label \ Text"
- set "Customized View Label" flag and open 'A' (Text Formatting)
- find Rotation symbol and Angle formatting and place it to the end

Rotation symbol formatting: <$ro>
Angle Reference formatting: <WRefXXX*0@$VIEW_ROTATION_ANGLE>

Please also take into account different 'Character Height Factors', which you set in the "Section View Settings \ Section Label" window: <CXXX> in formatting.
e.g. <C1.4000>, <C0.5000>, <C1.0000>

Example of result formatting without 'Character Height Factor':

<W&Ref1*0@VWLETTER_DISP>-<W&Ref1*0@VWLETTER_DISP> (<W&Ref2*0@VWSCALE>)<$ro> <WRef3*0@$VIEW_ROTATION_ANGLE>

Notes and References

IR_10056103

Hardware/Software Configuration

Platform: na
OS: windows
OS Version: n/a
Product: NX
Application: DRAFTING
Version: V1953
Function: DRAWING/VIEW

Ref: 002-8543279