NX Stub length of PMI surface finish symbol differs when inherrited to drawing view

In modelling there is a surface finish PMI symbol with a specific stub length defined. When the modelling view is added to a master model drawing and PMI is inherited, the stub length setting in drafting is lost and default stub length is used instead.

How to make NX inherit the setting for the stub length in drafting?

Solution

By default Inherited PMI honors the all the drafting preferences of the drawing part. In the described scenario the workflow inherited PMI takes the leader stub length of the drawing part. This is as per design.

If the user wants to match the stub length of the model PMI then LeaderStubLength tracking property should be turned on.
This Property can be turned on using Menu --> Format --> PMI --> Inherit PMI Tracking.



Note: The 'Inherit PMI Tracking' settings are specific to each drawing.


To make the Inherit PMI Tracking settings the same for all new drawings these properties need to be set in the drawing templates.

To inherit particular properties from the PMI annotation by default for this property you need to modify 
%UGII_BASE_DIR%\ugii\pmi\property\inherit.xml and change
from
    <Property name="StubLength">
        <Operation>none</Operation>
    </Property>
to
    <Property name="StubLength">
        <Operation>track</Operation>
    </Property>

Notes and References

For further information please refer to the NX Documentation, Design (CAD) -> Product and Manufacturing Information (PMI) -> PMI and drawings -> Inheriting PMI into a drawing -> Synchronizing PMI properties.

Hardware/Software Configuration

Platform: INTL64
OS: window
OS Version: 1064
Product: NX
Application: PMI
Version: V12.0.2
Function: INHERIT_TO_DRAW

Ref: 002-8013967