How to drive a Drawing section line's position using a dimension.
Solution
NX allows the creation of a sketch curve to position the Section Line and then
create a driving dimension to re-position the Section Line as needed.
1. In the Part Navigator, hover the cursor over the Parent view (of the
Section view to be created), 'MouseButton3 (MB3)-->Active Sketch
View'.
Note: Direct Sketch curves can now be added associatively to the
Parent view.
2. Insert a Sketch line segment (Vertical or Horizontal) in the Parent
view where the initial cut location of the Section line will be.
3. Select the 'Finish' icon to finish the sketch.
4. Select the 'Section View' icon.
5. For the Cut position, select the control point of the sketch curve
from Step 3 and create the Section Line.
6. Place the Section View.
7. Select the 'Linear Dimension' icon.
NOTE: Confirm the 'Driving Method' is set to 'Driving'.
8. Select the Sketch curve from Step 3 for the first object.
Select the second object and place the dimension.
Note: The Section Line is now associated to the sketch curve and
can be moved if the dimension is modified.
To modify the dimension that moves the Section Line:
1. Double-click the dimension to edit it.
2. On the Dimension dialog, enter a new value to move the sketch curve.
4. Update the drawing, and the Section View will update.
Notes and References
Hardware/Software Configuration
Platform: all
OS: n/a
OS Version: n/a
Product: NX
Application: DRAFTING
Version: V9.0
Function: DRAWING/VIEW
Ref: 001-8803467