How to display a model in a drawing view and show only specific features of the
model.
Solution
1. In the Modeling application, with the model as the displayed part, select
in the Menu, 'Insert-->Associative Copy-->Extract Geometry'.
2. Set Type to 'Body'.
3. In the Settings grouping, toggle on 'Fix at Current Timestamp'.
This will create an associative copy of the solid with only the features
created before the current Timestamp.
4. In the Menu, select 'Format-->Move to Layer'.
5. Select the extracted body.
6. OK the dialog.
7. Specify a unique layer for the extracted body.
8. [Optional] If needed, repeat steps 1-8 to create an extracted body
for each set of features to display in a drawing view.
9. Switch to the Drafting application with the drawing as the displayed part.
10. Place a view on the drawing.
11. In the Menu, select 'Format-->Layer Visible In View'.
12. Make the layer visible that contains the extracted body with the
desired features to be displayed.
13. Make all other layers Invisible.
This technique can be used to show the same solid in various stages of
development in separate drawing views.
Notes and References
Hardware/Software Configuration
Platform: all
OS: n/a
OS Version: n/a
Product: NX
Application: DRAFTING
Version: V9.0
Function: DRAWING/VIEW
Ref: 001-8946771